Create an emboss

There are many ways to create an emboss. The example below uses basic options.

1. Choose Home tab → Base group → Emboss to open the Emboss dialog box.

2. Click Curve and select a closed section of edges or curves. If you select a planar face for the section, the Sketch opens to let you create a section on that face. Selection Intent is available. You can also click Sketch Section to open the Sketch and create a new section on a specified plane.

3. In the Face to Emboss group, click Select Face and select one or more connected faces to emboss. Selection Intent is available.

4. (Optional) In the Emboss Direction group, specify a new emboss draw direction. The default emboss direction is normal to the plane of the section.

5. In the End Cap group, use one or more of the following options to specify how to cap the sidewall geometry:

   • Geometry — Specify the source geometry for the end cap (Plane of Section, Embossed Faces, Datum Plane, or Selected Faces).
   • Location — Specify the process to apply to the source geometry to create the end cap (In Place, Offset, or Translate).
   • Distance — Specify how far the end cap is offset or translated from the source geometry.

6. In the Draft group, use the following options to define the shape of the sidewall:

   • Draft — Specify the location that is held stationary during the draft operation (From End Cap, From Embossed Faces, From Selected Face, From Selected Datum, From Section, or None).
   • Draft Method — Specify how the draft is applied to the sidewalls (Isocline Draft, True Draft, Surface Draft). This dictates the direction that the angle is measured from.
   • Draft Angle — Specify the angles of individual sidewalls.

   Depending on which Draft options you choose, you may have to select additional objects. (Example used here: Draft Method = True Draft, Draft option = End Cap.)

7. (Optional) Set or change additional options: Convexity and Approximate Offset Surface in the Settings group, and Free Edge Vector in the Free Edge Trimming group.

8. If the preview disappears, the current combination of options and parameters are invalid for the selected geometry — change them until you get a valid preview. When the preview shows the emboss you want, click OK or Apply to create the feature.

Related

• Emboss
• Emboss options
• Understanding Emboss options

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Create an emboss, NX 2212 Series © 2023 Siemens